The CompositeShellSection object defines the properties of a composite shell section.
The CompositeShellSection object is derived from the GeometryShellSection object.
sectionApi.sections()[name]
This method creates a CompositeShellSection object.
sectionApi.CompositeShellSection
odb_CompositeShellSection&
CompositeShellSection(const odb_String& name,
const odb_SequenceSectionLayer& layup,
bool symmetric,
const odb_String& thicknessType,
bool preIntegrate,
const odb_String& poissonDefinition,
double poisson,
const odb_String& integrationRule,
const odb_String& temperature,
const odb_String& idealization,
odb_Union nTemp,
odb_Union thicknessModulus,
bool useDensity,
double density,
const odb_String& layupName,
const odb_String& thicknessField,
const odb_String& nodalThicknessField);Required arguments
An odb_String specifying the repository key.
A sequence of SectionLayer objects specifying the shell cross-section.
Optional arguments
A Boolean specifying whether or not the layup should be made symmetric by the analysis. The default value is false.
An odb_String specifying the distribution used for defining the thickness of the elements. Possible values are "UNIFORM", "ANALYTICAL_FIELD", "DISCRETE_FIELD", "NODAL_ANALYTICAL_FIELD", and "NODAL_DISCRETE_FIELD". The default value is "UNIFORM".
A Boolean specifying whether the shell section properties are specified by the user prior to the analysis (true) or integrated during the analysis (false). The default value is false.
An odb_String specifying whether to use the default value for the Poisson's ratio. Possible values are:
The default value is "DEFAULT".
"DEFAULT", specifying that the default value for the Poisson's ratio is 0.5 in an Abaqus/Standard analysis and is obtained from the material definition in an Abaqus/Explicit analysis.
"VALUE", specifying that the Poisson's ratio used in the analysis is the value provided in poisson.
A Double specifying the Poisson's ratio. Possible values are –1.0
poisson
An odb_String specifying the shell section integration rule. Possible values are "SIMPSON" and "GAUSS". The default value is "SIMPSON".
An odb_String specifying the mode used for temperature and field variable input across the section thickness. Possible values are "GRADIENT" and "POINTWISE". The default value is "GRADIENT".
An odb_String specifying the mechanical idealization used for the section calculations. This member is only applicable when preIntegrate is set to true. Possible values are "NO_IDEALIZATION", "SMEAR_ALL_LAYERS", "MEMBRANE", and "BENDING". The default value is "NO_IDEALIZATION".
The string "NONE" or an Int specifying the number of temperature points to be input. This argument is valid only when temperature="POINTWISE". The default value is "NONE".
The string "NONE" or a Double specifying the effective thickness modulus. This argument is relevant only for continuum shells and must be used in conjunction with the argument poisson. The default value is "NONE".
A Boolean specifying whether or not to use the value of density. The default value is false.
A Double specifying the value of density to apply to this section. The default value is 0.0.
An odb_String specifying the layup name for this section. The default value is an empty string.
An odb_String specifying the name of the AnalyticalField or DiscreteField object used to define the thickness of the shell elements. The thicknessField argument applies only when thicknessType="ANALYTICAL_FIELD" or thicknessType="DISCRETE_FIELD". The default value is an empty string.
An odb_String specifying the name of the AnalyticalField or DiscreteField object used to define the thickness of the shell elements at each node. The nodalThicknessField argument applies only when thicknessType="NODAL_ANALYTICAL_FIELD" or thicknessType="NODAL_DISCRETE_FIELD". The default value is an empty string.
Return value
A CompositeShellSection object.
Exceptions
The CompositeShellSection object has members with the same names and descriptions as the arguments to the CompositeShellSection method.
In addition, the CompositeShellSection object can have the following members:
odb_RebarLayers rebarLayers() const; odb_TransverseShearShell transverseShear() const;
A RebarLayers object specifying reinforcement properties.
A TransverseShearShell object specifying the transverse shear stiffness properties.