Products: Abaqus/Standard Abaqus/Explicit Abaqus/CAE
| CPE3 | 3-node linear |
| CPE3H(S) | 3-node linear, hybrid with constant pressure |
| CPE4(S) | 4-node bilinear |
| CPE4H(S) | 4-node bilinear, hybrid with constant pressure |
| CPE4I(S) | 4-node bilinear, incompatible modes |
| CPE4IH(S) | 4-node bilinear, incompatible modes, hybrid with linear pressure |
| CPE4R | 4-node bilinear, reduced integration with hourglass control |
| CPE4RH(S) | 4-node bilinear, reduced integration with hourglass control, hybrid with constant pressure |
| CPE6(S) | 6-node quadratic |
| CPE6H(S) | 6-node quadratic, hybrid with linear pressure |
| CPE6M | 6-node modified, with hourglass control |
| CPE6MH(S) | 6-node modified, with hourglass control, hybrid with linear pressure |
| CPE8(S) | 8-node biquadratic |
| CPE8H(S) | 8-node biquadratic, hybrid with linear pressure |
| CPE8R(S) | 8-node biquadratic, reduced integration |
| CPE8RH(S) | 8-node biquadratic, reduced integration, hybrid with linear pressure |
The constant pressure hybrid elements have one additional variable relating to pressure, and the linear pressure hybrid elements have three additional variables relating to pressure.
Element types CPE4I and CPE4IH have five additional variables relating to the incompatible modes.
Element types CPE6M and CPE6MH have two additional displacement variables.
| CPS3 | 3-node linear |
| CPS4(S) | 4-node bilinear |
| CPS4I(S) | 4-node bilinear, incompatible modes |
| CPS4R | 4-node bilinear, reduced integration with hourglass control |
| CPS6(S) | 6-node quadratic |
| CPS6M | 6-node modified, with hourglass control |
| CPS8(S) | 8-node biquadratic |
| CPS8R(S) | 8-node biquadratic, reduced integration |
| CPEG3(S) | 3-node linear triangle |
| CPEG3H(S) | 3-node linear triangle, hybrid with constant pressure |
| CPEG4(S) | 4-node bilinear quadrilateral |
| CPEG4H(S) | 4-node bilinear quadrilateral, hybrid with constant pressure |
| CPEG4I(S) | 4-node bilinear quadrilateral, incompatible modes |
| CPEG4IH(S) | 4-node bilinear quadrilateral, incompatible modes, hybrid with linear pressure |
| CPEG4R(S) | 4-node bilinear quadrilateral, reduced integration with hourglass control |
| CPEG4RH(S) | 4-node bilinear quadrilateral, reduced integration with hourglass control, hybrid with constant pressure |
| CPEG6(S) | 6-node quadratic triangle |
| CPEG6H(S) | 6-node quadratic triangle, hybrid with linear pressure |
| CPEG6M(S) | 6-node modified, with hourglass control |
| CPEG6MH(S) | 6-node modified, with hourglass control, hybrid with linear pressure |
| CPEG8(S) | 8-node biquadratic quadrilateral |
| CPEG8H(S) | 8-node biquadratic quadrilateral, hybrid with linear pressure |
| CPEG8R(S) | 8-node biquadratic quadrilateral, reduced integration |
| CPEG8RH(S) | 8-node biquadratic quadrilateral, reduced integration, hybrid with linear pressure |
The constant pressure hybrid elements have one additional variable relating to pressure, and the linear pressure hybrid elements have three additional variables relating to pressure.
Element types CPEG4I and CPEG4IH have five additional variables relating to the incompatible modes.
Element types CPEG6M and CPEG6MH have two additional displacement variables.
| CPE3T | 3-node linear displacement and temperature |
| CPE4T(S) | 4-node bilinear displacement and temperature |
| CPE4HT(S) | 4-node bilinear displacement and temperature, hybrid with constant pressure |
| CPE4RT | 4-node bilinear displacement and temperature, reduced integration with hourglass control |
| CPE4RHT(S) | 4-node bilinear displacement and temperature, reduced integration with hourglass control, hybrid with constant pressure |
| CPE6MT | 6-node modified displacement and temperature, with hourglass control |
| CPE6MHT(S) | 6-node modified displacement and temperature, with hourglass control, hybrid with constant pressure |
| CPE8T(S) | 8-node biquadratic displacement, bilinear temperature |
| CPE8HT(S) | 8-node biquadratic displacement, bilinear temperature, hybrid with linear pressure |
| CPE8RT(S) | 8-node biquadratic displacement, bilinear temperature, reduced integration |
| CPE8RHT(S) | 8-node biquadratic displacement, bilinear temperature, reduced integration, hybrid with linear pressure |
1, 2, 11 at corner nodes
1, 2 at midside nodes of second-order elements in Abaqus/Standard
1, 2, 11 at midside nodes of modified displacement and temperature elements in Abaqus/Standard
The constant pressure hybrid elements have one additional variable relating to pressure, and the linear pressure hybrid elements have three additional variables relating to pressure.
Element types CPE6MT and CPE6MHT have two additional displacement variables and one additional temperature variable.
| CPS3T | 3-node linear displacement and temperature |
| CPS4T(S) | 4-node bilinear displacement and temperature |
| CPS4RT | 4-node bilinear displacement and temperature, reduced integration with hourglass control |
| CPS6MT | 6-node modified displacement and temperature, with hourglass control |
| CPS8T(S) | 8-node biquadratic displacement, bilinear temperature |
| CPS8RT(S) | 8-node biquadratic displacement, bilinear temperature, reduced integration |
| CPEG3T(S) | 3-node linear displacement and temperature |
| CPEG3HT(S) | 3-node linear displacement and temperature, hybrid with constant pressure |
| CPEG4T(S) | 4-node bilinear displacement and temperature |
| CPEG4HT(S) | 4-node bilinear displacement and temperature, hybrid with constant pressure |
| CPEG4RT(S) | 4-node bilinear displacement and temperature, reduced integration with hourglass control |
| CPEG4RHT(S) | 4-node bilinear displacement and temperature, reduced integration with hourglass control, hybrid with constant pressure |
| CPEG6MT(S) | 6-node modified displacement and temperature, with hourglass control |
| CPEG6MHT(S) | 6-node modified displacement and temperature, with hourglass control, hybrid with constant pressure |
| CPEG8T(S) | 8-node biquadratic displacement, bilinear temperature |
| CPEG8HT(S) | 8-node biquadratic displacement, bilinear temperature, hybrid with linear pressure |
| CPEG8RHT(S) | 8-node biquadratic displacement, bilinear temperature, reduced integration, hybrid with linear pressure |
1, 2, 11 at corner nodes
1, 2 at midside nodes of second-order elements
1, 2, 11 at midside nodes of modified displacement and temperature elements
3, 4, 5 at the reference node
The constant pressure hybrid elements have one additional variable relating to pressure, and the linear pressure hybrid elements have three additional variables relating to pressure.
Element types CPEG6MT and CPEG6MHT have two additional displacement variables and one additional temperature variable.
| DC2D3(S) | 3-node linear |
| DC2D4(S) | 4-node linear |
| DC2D6(S) | 6-node quadratic |
| DC2D8(S) | 8-node biquadratic |
| DC2D3E(S) | 3-node linear |
| DC2D4E(S) | 4-node linear |
| DC2D6E(S) | 6-node quadratic |
| DC2D8E(S) | 8-node biquadratic |
| CPE4P(S) | 4-node bilinear displacement and pore pressure |
| CPE4PH(S) | 4-node bilinear displacement and pore pressure, hybrid with constant pressure stress |
| CPE4RP(S) | 4-node bilinear displacement and pore pressure, reduced integration with hourglass control |
| CPE4RPH(S) | 4-node bilinear displacement and pore pressure, reduced integration with hourglass control, hybrid with constant pressure |
| CPE6MP(S) | 6-node modified displacement and pore pressure, with hourglass control |
| CPE6MPH(S) | 6-node modified displacement and pore pressure, with hourglass control, hybrid with linear pressure |
| CPE8P(S) | 8-node biquadratic displacement, bilinear pore pressure |
| CPE8PH(S) | 8-node biquadratic displacement, bilinear pore pressure, hybrid with linear pressure stress |
| CPE8RP(S) | 8-node biquadratic displacement, bilinear pore pressure, reduced integration |
| CPE8RPH(S) | 8-node biquadratic displacement, bilinear pore pressure, reduced integration, hybrid with linear pressure stress |
1, 2, 8 at corner nodes
1, 2 at midside nodes for all elements except CPE6MP and CPE6MPH, which also have degree of freedom 8 active at midside nodes
The constant pressure hybrid elements have one additional variable relating to the effective pressure stress, and the linear pressure hybrid elements have three additional variables relating to the effective pressure stress to permit fully incompressible material modeling.
Element types CPE6MP and CPE6MPH have two additional displacement variables and one additional pore pressure variable.
| AC2D3 | 3-node linear |
| AC2D4(S) | 4-node bilinear |
| AC2D4R(E) | 4-node bilinear, reduced integration with hourglass control |
| AC2D6(S) | 6-node quadratic |
| AC2D8(S) | 8-node biquadratic |
| CPE3E(S) | 3-node linear |
| CPE4E(S) | 4-node bilinear |
| CPE6E(S) | 6-node quadratic |
| CPE8E(S) | 8-node biquadratic |
| CPE8RE(S) | 8-node biquadratic, reduced integration |
| CPS3E(S) | 3-node linear |
| CPS4E(S) | 4-node bilinear |
| CPS6E(S) | 6-node quadratic |
| CPS8E(S) | 8-node biquadratic |
| CPS8RE(S) | 8-node biquadratic, reduced integration |
| EMC2D3(S) | 3-node zero-order |
| EMC2D4(S) | 4-node zero-order |
Magnetic vector potential (for more information, see “Boundary conditions” in “Time-harmonic eddy current analysis,” Section 6.7.5).
For all elements except generalized plane strain elements, you must provide the element thickness; by default, unit thickness is assumed.
For generalized plane strain elements, you must provide three values: the initial length of the axial material fiber through the reference node, the initial value of 
(in radians), and the initial value of 
(in radians). If you do not provide these values, Abaqus assumes the default values of one unit as the initial length and zero for and . In addition, you must define the reference point for generalized plane strain elements.
| Input File Usage: | Use the following option to define the element properties for all elements except generalized plane strain elements: |
*SOLID SECTION Use the following option to define the element properties for generalized plane strain elements: *SOLID SECTION, REF NODE=node number or node set name |
| Abaqus/CAE Usage: | Property module: Create Section: select Solid as the section Category and Homogeneous or Generalized plane strain as the section Type |
Generalized plane strain sections must be assigned to regions of parts that have a reference point associated with them. To define the reference point: Part module: Tools |
Distributed loads are available for all elements with displacement degrees of freedom. They are specified as described in “Distributed loads,” Section 32.4.3.
Load ID (*DLOAD): BX
Abaqus/CAE Load/Interaction: Body force
Units: FL–3
Description: Body force in global X-direction.
Load ID (*DLOAD): BY
Abaqus/CAE Load/Interaction: Body force
Units: FL–3
Description: Body force in global Y-direction.
Load ID (*DLOAD): BXNU
Abaqus/CAE Load/Interaction: Body force
Units: FL–3
Description: Nonuniform body force in global X-direction with magnitude supplied via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): BYNU
Abaqus/CAE Load/Interaction: Body force
Units: FL–3
Description: Nonuniform body force in global Y-direction with magnitude supplied via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): CENT(S)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–4(ML–3T–2)
Description: Centrifugal load (magnitude is input as 
, where 
is the mass density per unit volume, 
is the angular velocity). Not available for pore pressure elements.
Load ID (*DLOAD): CENTRIF(S)
Abaqus/CAE Load/Interaction: Rotational body force
Units: T–2
Description: Centrifugal load (magnitude is input as 
, where is the angular velocity).
Load ID (*DLOAD): CORIO(S)
Abaqus/CAE Load/Interaction: Coriolis force
Units: FL–4T (ML–3T–1)
Description: Coriolis force (magnitude is input as 
, where is the mass density per unit volume, is the angular velocity). Not available for pore pressure elements.
Load ID (*DLOAD): GRAV
Abaqus/CAE Load/Interaction: Gravity
Units: LT–2
Description: Gravity loading in a specified direction (magnitude is input as acceleration).
Load ID (*DLOAD): HPn(S)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–2
Description: Hydrostatic pressure on face n, linear in global Y.
Load ID (*DLOAD): Pn
Abaqus/CAE Load/Interaction: Pressure
Units: FL–2
Description: Pressure on face n.
Load ID (*DLOAD): PnNU
Abaqus/CAE Load/Interaction: Not supported
Units: FL–2
Description: Nonuniform pressure on face n with magnitude supplied via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DLOAD): ROTA(S)
Abaqus/CAE Load/Interaction: Rotational body force
Units: T–2
Description: Rotary acceleration load (magnitude is input as 
, where is the rotary acceleration).
Load ID (*DLOAD): SBF(E)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–5T2
Description: Stagnation body force in global X- and Y-directions.
Load ID (*DLOAD): SPn(E)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–4T2
Description: Stagnation pressure on face n.
Load ID (*DLOAD): TRSHRn
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: Shear traction on face n.
Load ID (*DLOAD): TRSHRnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–2
Description: Nonuniform shear traction on face n with magnitude and direction supplied via user subroutine UTRACLOAD.
Load ID (*DLOAD): TRVECn
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: General traction on face n.
Load ID (*DLOAD): TRVECnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–2
Description: Nonuniform general traction on face n with magnitude and direction supplied via user subroutine UTRACLOAD.
Load ID (*DLOAD): VBF(E)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–4T
Description: Viscous body force in global X- and Y-directions.
Load ID (*DLOAD): VPn(E)
Abaqus/CAE Load/Interaction: Not supported
Units: FL–3T
Description: Viscous pressure on face n, applying a pressure proportional to the velocity normal to the face and opposing the motion.
Foundations are available for Abaqus/Standard elements with displacement degrees of freedom. They are specified as described in “Element foundations,” Section 2.2.2.
Load ID (*FOUNDATION): Fn(S)
Abaqus/CAE Load/Interaction: Elastic foundation
Units: FL–3
Description: Elastic foundation on face n.
Distributed heat fluxes are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*DFLUX): BF
Abaqus/CAE Load/Interaction: Body heat flux
Units: JL–3T–1
Description: Heat body flux per unit volume.
Load ID (*DFLUX): BFNU(S)
Abaqus/CAE Load/Interaction: Body heat flux
Units: JL–3T–1
Description: Nonuniform heat body flux per unit volume with magnitude supplied via user subroutine DFLUX.
Load ID (*DFLUX): Sn
Abaqus/CAE Load/Interaction: Surface heat flux
Units: JL–2T–1
Description: Heat surface flux per unit area into face n.
Load ID (*DFLUX): SnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: JL–2T–1
Description: Nonuniform heat surface flux per unit area into face n with magnitude supplied via user subroutine DFLUX.
Film conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*FILM): Fn
Abaqus/CAE Load/Interaction: Surface film condition
Units: JL–2T–1
–1
Description: Film coefficient and sink temperature (units of ) provided on face n.
Load ID (*FILM): FnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: JL–2T–1–1
Description: Nonuniform film coefficient and sink temperature (units of ) provided on face n with magnitude supplied via user subroutine FILM.
Radiation conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*RADIATE): Rn
Abaqus/CAE Load/Interaction: Surface radiation
Units: Dimensionless
Description: Emissivity and sink temperature (units of ) provided on face n.
Distributed flows are available for all elements with pore pressure degrees of freedom. They are specified as described in “Pore fluid flow,” Section 32.4.7.
Load ID (*FLOW/ *DFLOW): Qn(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Seepage (outward normal flow) proportional to the difference between surface pore pressures and a reference sink pore pressure on face n (units of FL–2).
Load ID (*FLOW/ *DFLOW): QnD(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Drainage-only seepage (outward normal flow) proportional to the surface pore pressure on face n only when that pressure is positive.
Load ID (*FLOW/ *DFLOW): QnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Nonuniform seepage (outward normal flow) proportional to the difference between surface pore pressures and a reference sink pore pressure on face n (units of FL–2) with magnitude supplied via user subroutine FLOW.
Load ID (*FLOW/ *DFLOW): Sn(S)
Abaqus/CAE Load/Interaction: Surface pore fluid
Units: LT–1
Description: Prescribed pore fluid effective velocity (outward from the face) on face n.
Load ID (*FLOW/ *DFLOW): SnNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: LT–1
Description: Nonuniform prescribed pore fluid effective velocity (outward from the face) on face n with magnitude supplied via user subroutine DFLOW.
Distributed impedances are available for all elements with acoustic pressure degrees of freedom. They are specified as described in “Acoustic and shock loads,” Section 32.4.6.
Load ID (*IMPEDANCE): In
Abaqus/CAE Load/Interaction: Not supported
Units: None
Description: Name of the impedance property that defines the impedance on face n.
Electric fluxes are available for piezoelectric elements. They are specified as described in “Piezoelectric analysis,” Section 6.7.2.
Load ID (*DECHARGE): EBF(S)
Abaqus/CAE Load/Interaction: Body charge
Units: CL–3
Description: Body flux per unit volume.
Load ID (*DECHARGE): ESn(S)
Abaqus/CAE Load/Interaction: Surface charge
Units: CL–2
Description: Prescribed surface charge on face n.
Distributed electric current densities are available for coupled thermal-electrical elements and electromagnetic elements. They are specified as described in “Coupled thermal-electrical analysis,” Section 6.7.3, for thermal-electrical elements and in “Time-harmonic eddy current analysis,” Section 6.7.5, for electromagnetic elements.
Load ID (*DECURRENT): CBF(S)
Abaqus/CAE Load/Interaction: Body current
Units: CL–3T–1
Description: Volumetric current source density.
Load ID (*DECURRENT): CSn(S)
Abaqus/CAE Load/Interaction: Surface current
Units: CL–2T–1
Description: Current density on face n.
Load ID (*DECURRENT): CJ(S)
Abaqus/CAE Load/Interaction: Not supported
Units: CL–2T–1
Description: Volume current density vector in an eddy current analysis.
Distributed concentration fluxes are available for mass diffusion elements. They are specified as described in “Mass diffusion analysis,” Section 6.9.1.
Load ID (*DFLUX): BF(S)
Abaqus/CAE Load/Interaction: Body concentration flux
Units: PT–1
Description: Concentration body flux per unit volume.
Load ID (*DFLUX): BFNU(S)
Abaqus/CAE Load/Interaction: Body concentration flux
Units: PT–1
Description: Nonuniform concentration body flux per unit volume with magnitude supplied via user subroutine DFLUX.
Load ID (*DFLUX): Sn(S)
Abaqus/CAE Load/Interaction: Surface concentration flux
Units: PLT–1
Description: Concentration surface flux per unit area into face n.
Load ID (*DFLUX): SnNU(S)
Abaqus/CAE Load/Interaction: Surface concentration flux
Units: PLT–1
Description: Nonuniform concentration surface flux per unit area into face n with magnitude supplied via user subroutine DFLUX.
Surface-based distributed loads are available for all elements with displacement degrees of freedom. They are specified as described in “Distributed loads,” Section 32.4.3.
Load ID (*DSLOAD): HP(S)
Abaqus/CAE Load/Interaction: Pressure
Units: FL–2
Description: Hydrostatic pressure on the element surface, linear in global Y.
Load ID (*DSLOAD): P
Abaqus/CAE Load/Interaction: Pressure
Units: FL–2
Description: Pressure on the element surface.
Load ID (*DSLOAD): PNU
Abaqus/CAE Load/Interaction: Pressure
Units: FL–2
Description: Nonuniform pressure on the element surface with magnitude supplied via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit.
Load ID (*DSLOAD): SP(E)
Abaqus/CAE Load/Interaction: Pressure
Units: FL–4T2
Description: Stagnation pressure on the element surface.
Load ID (*DSLOAD): TRSHR
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: Shear traction on the element surface.
Load ID (*DSLOAD): TRSHRNU(S)
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: Nonuniform shear traction on the element surface with magnitude and direction supplied via user subroutine UTRACLOAD.
Load ID (*DSLOAD): TRVEC
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: General traction on the element surface.
Load ID (*DSLOAD): TRVECNU(S)
Abaqus/CAE Load/Interaction: Surface traction
Units: FL–2
Description: Nonuniform general traction on the element surface with magnitude and direction supplied via user subroutine UTRACLOAD.
Load ID (*DSLOAD): VP(E)
Abaqus/CAE Load/Interaction: Pressure
Units: FL–3T
Description: Viscous pressure on the element surface. The viscous pressure is proportional to the velocity normal to the element surface and opposing the motion.
Surface-based heat fluxes are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*DSFLUX): S
Abaqus/CAE Load/Interaction: Surface heat flux
Units: JL–2T–1
Description: Heat surface flux per unit area into the element surface.
Load ID (*DSFLUX): SNU(S)
Abaqus/CAE Load/Interaction: Surface heat flux
Units: JL–2T–1
Description: Nonuniform heat surface flux per unit area applied on the element surface with magnitude supplied via user subroutine DFLUX.
Surface-based film conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*SFILM): F
Abaqus/CAE Load/Interaction: Surface film condition
Units: JL–2T–1–1
Description: Film coefficient and sink temperature (units of ) provided on the element surface.
Load ID (*SFILM): FNU(S)
Abaqus/CAE Load/Interaction: Surface film condition
Units: JL–2T–1–1
Description: Nonuniform film coefficient and sink temperature (units of ) provided on the element surface with magnitude supplied via user subroutine FILM.
Surface-based radiation conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 32.4.4.
Load ID (*SRADIATE): R
Abaqus/CAE Load/Interaction: Surface radiation
Units: Dimensionless
Description: Emissivity and sink temperature (units of ) provided on the element surface.
Surface-based flows are available for all elements with pore pressure degrees of freedom. They are specified as described in “Pore fluid flow,” Section 32.4.7.
Load ID (*SFLOW/ *DSFLOW): Q(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Seepage (outward normal flow) proportional to the difference between surface pore pressures and a reference sink pore pressure on the element surface (units of FL–2).
Load ID (*SFLOW/ *DSFLOW): QD(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Drainage-only seepage (outward normal flow) proportional to the surface pore pressure on the element surface only when that pressure is positive.
Load ID (*SFLOW/ *DSFLOW): QNU(S)
Abaqus/CAE Load/Interaction: Not supported
Units: F–1L3T–1
Description: Nonuniform seepage (outward normal flow) proportional to the difference between surface pore pressures and a reference sink pore pressure on the element surface (units of FL–2) with magnitude supplied via user subroutine FLOW.
Load ID (*SFLOW/ *DSFLOW): S(S)
Abaqus/CAE Load/Interaction: Surface pore fluid
Units: LT–1
Description: Prescribed pore fluid effective velocity outward from the element surface.
Load ID (*SFLOW/ *DSFLOW): SNU(S)
Abaqus/CAE Load/Interaction: Surface pore fluid
Units: LT–1
Description: Nonuniform prescribed pore fluid effective velocity (outward from the surface) on the element surface with magnitude supplied via user subroutine DFLOW.
Surface-based impedances are available for all elements with acoustic pressure degrees of freedom. They are specified as described in “Acoustic and shock loads,” Section 32.4.6.
Surface-based incident wave loads are available for all elements with displacement degrees of freedom or acoustic pressure degrees of freedom. They are specified as described in “Acoustic and shock loads,” Section 32.4.6. If the incident wave field includes a reflection off a plane outside the boundaries of the mesh, this effect can be included.
Surface-based electric fluxes are available for piezoelectric elements. They are specified as described in “Piezoelectric analysis,” Section 6.7.2.
Load ID (*DSECHARGE): ES(S)
Abaqus/CAE Load/Interaction: Surface charge
Units: CL–2
Description: Prescribed surface charge on the element surface.
Surface-based electric current densities are available for coupled thermal-electrical elements. They are specified as described in “Coupled thermal-electrical analysis,” Section 6.7.3.
Load ID (*DSECURRENT): CS(S)
Abaqus/CAE Load/Interaction: Surface current
Units: CL–2T–1
Description: Current density applied on the element surface.
Load ID (*DSECURRENT): CK(S)
Abaqus/CAE Load/Interaction: Not supported
Units: CL–1T–1
Description: Surface current density vector in an eddy current analysis.
For most elements output is in global directions unless a local coordinate system is assigned to the element through the section definition (“Orientations,” Section 2.2.5) in which case output is in the local coordinate system (which rotates with the motion in large-displacement analysis). In the case of electromagnetic elements, vector output is always in the global system. See “State storage,” Section 1.5.4 of the Abaqus Theory Manual, for details.
Stress and other tensors (including strain tensors) are available for elements with displacement degrees of freedom. All tensors have the same components. For example, the stress components are as follows:
S11 |
|
S22 |
|
S33 |
|
S12 |
|
Available for elements with temperature degrees of freedom.
HFL1 | Heat flux in the X-direction. |
HFL2 | Heat flux in the Y-direction. |
Available for elements with pore pressure degrees of freedom.
FLVEL1 | Pore fluid effective velocity in the X-direction. |
FLVEL2 | Pore fluid effective velocity in the Y-direction. |
Available for elements with normalized concentration degrees of freedom.
MFL1 | Concentration flux in the X-direction. |
MFL2 | Concentration flux in the Y-direction. |
Available for elements with electrical potential degrees of freedom.
EPG1 | Electrical potential gradient in the X-direction. |
EPG2 | Electrical potential gradient in the Y-direction. |
Available for piezoelectric elements.
EFLX1 | Electrical flux in the X-direction. |
EFLX2 | Electrical flux in the Y-direction. |
Available for coupled thermal-electrical elements.
ECD1 | Electrical current density in the X-direction. |
ECD2 | Electrical current density in the Y-direction. |
Available for electromagnetic elements.
EME1 | Electric field in the X-direction. |
EME2 | Electric field in the Y-direction. |
Available for electromagnetic elements.
EMB3 | Magnetic flux density in the Z-direction. |
For generalized plane strain elements, the reference node associated with each element (where the generalized plane strain degrees of freedom are stored) is not shown. The reference node should be the same for all elements in any given connected region so that the bounding planes are the same for that region. Different regions may have different reference nodes. The number of the reference node is not incremented when the elements are generated incrementally (see “Creating elements from existing elements by generating them incrementally” in “Element definition,” Section 2.2.1).
, direct stress.
, direct stress.
, direct stress (not available for plane stress elements).
, shear stress.